Uretyco
Make it now
Sheet Metal & Laser Cutting: Bend Allowance, K-Factor, and DXF Hygiene

Sheet Metal & Laser Cutting: Bend Allowance, K-Factor, and DXF Hygiene

May 02, 20268 min readManufacturing MethodsUretyco Engineering · Sheet Metal & Fabrication
Sheet MetalLaser CuttingDXFK-FactorDesign Guide

Sheet metal DFM for laser-cut and pressed parts: minimum bend radii, K-factor by material, hole-to-edge distance, bend reliefs, and how to send a DXF that does not get rejected.

Sheet metal is the most cost-sensitive process to model correctly. A drawing with imprecise bend allowances or a DXF with overlapping lines forces our partner to either ask questions (slowing the quote) or guess (creating rework risk). Both outcomes are fixable in the design phase.

K-factor and bend allowance fundamentals

The K-factor describes where the neutral fiber sits inside the bend. If your CAD package uses a generic K of 0.44 you will be close on aluminum and mild steel but off on stainless or thicker stock. Use the values below as starting points and refine based on supplier feedback.

MaterialThicknessInside radiusK-factor
Aluminum 5052≤ 1.5 mm= thickness0.40
Aluminum 50521.5–3 mm= thickness0.43
Mild steel 1008/CR4≤ 2 mm= thickness0.42
Stainless 304≤ 2 mm1.5x thickness0.45
Stainless 3042–3 mm1.5x thickness0.47

Minimum bends, holes, and edges

  • Minimum hole diameter: ≥ thickness; tighter than that requires drilling instead of laser piercing.
  • Minimum hole-to-edge distance: 2x thickness.
  • Minimum hole-to-bend distance: 3x thickness from the bend tangent line.
  • Minimum bend-to-bend distance: 6x thickness, plus the bend radii.
  • Bend reliefs: at least thickness wide and 1.5x thickness deep.
Bend reliefs save parts

Forgetting reliefs at the corners of a bend that meets an edge is the #1 reason for cracks in stainless and aluminum. Add them in CAD before exporting flat patterns.

DXF hygiene

Most laser shops will only cut clean DXFs. Clean means closed contours, no overlapping lines, no zero-length segments, and no spline-only curves where polyline-arc representations are expected. The Uretyco platform runs an automated check on upload and surfaces issues before quoting.

  • Use millimeters, set units explicitly in the DXF header, and state them in the project notes or drawing as well.
  • Convert splines to polylines when possible; complex splines slow down the laser controller.
  • Keep dimensions, text, and title blocks out of the DXF and put them in the PDF drawing; include text only if it is meant to be etched or cut, on a clearly named layer.
  • For a bent part, upload the 3D STEP model of the formed part and add the flat-pattern DXF to it as an attachment; a technical drawing as DXF with a flat pattern and bend lines that the platform confirms also works.

Realistic tolerances

FeatureAchievable tolerance
Cut edge length (laser)±0.10 mm
Hole diameter (laser)±0.10 mm; for fits, drill instead
Bend angle±1° standard, ±0.5° on request
Flatness on parts > 300 mm1-2 mm warp possible
Hole position after bend±0.5 mm default

Edges and finishes

Laser-cut edges are slightly oxidized; ask for deburr if the part is handled. Powder coat and zinc plating are the most common downstream finishes. For stainless, brushed grain finish is a popular default.

Pre-upload checklist

  1. 1
    Export flat-pattern DXF

    Closed contours, no overlapping lines, mm units. It is the main file of a flat part and an attachment of a bent part.

  2. 2
    Provide STEP with bends

    The main file of a bent part. It also lets suppliers verify that the flat pattern matches the 3D model.

  3. 3
    Annotate bend lines and angles

    Down-bend vs up-bend, angle in degrees, inside radius.

  4. 4
    Specify material and grain

    Grade, gauge or thickness, grain direction if cosmetic.

  5. 5
    Call out finishes and hardware

    Powder coat, plating, PEM inserts, weld nuts, hardware BOM.

Related articles

Was this page helpful?

Can't find what you need? Contact our team for expert assistance with your manufacturing project.

Contact our team